Create account

GUIDE · METAL SPINNING PROGRAMMING

Metal spinning programming: a practical guide to CNC spinning and CAM

This guide brings together what you need to know when programming a CNC spinning lathe: spinning methods, blank diameter, spinning ratio, pass design, roller and mandrel, G-code structure, common defects and how to work with metal spinning CAM.

Last updated: · KSOTech Engineering Solutions

What is metal spinning?

Metal spinning is a chipless forming process in which a flat sheet (the blank) is pressed onto a rotating mandrel by a roller or tool to make a rotationally symmetric part. It is also called spin forming.

It is used for seamless, single-piece parts such as lighting reflectors, vessels, cones, domes, funnels and tank heads. Because tooling costs less than for deep drawing, it is a common choice for prototypes and small to medium batches.

In manual spinning a skilled spinner guides the roller lever by hand. On a CNC spinning lathe every roller pass is defined by a motion program. Metal spinning programming is the job of preparing that program.

Conventional spinning vs shear spinning

In conventional spinning the sheet is laid onto the mandrel step by step over several passes. Wall thickness stays roughly the same, and the blank is noticeably larger than the part's largest diameter.

In shear spinning the part is formed in one or a few passes and the wall is deliberately thinned. Material does not flow radially; it shifts along the axis. The blank diameter is therefore close to the part's largest diameter.

For cones, the wall thickness in shear spinning is estimated with the sine law, where α is the half-cone angle (between the wall and the axis):

t = t₀ · sin α

t₀: blank thickness · t: formed wall thickness

Conventional spinningShear spinningMandrelBlankPassesMandrelt = t₀ · sin α
Conventional spinning lays the sheet onto the mandrel over many passes; shear spinning thins it in one pass.

Example: a 2 mm blank and a 30° half-cone angle give a wall of about 2 × 0.5 = 1 mm. Real values vary with material, roller and process conditions.

How to calculate the blank diameter

In conventional spinning the wall thickness stays roughly constant, so a first estimate assumes the surface area is preserved. If A is the mid-surface area of the part, the blank diameter is given below.

For a flat-bottomed cylindrical cup (diameter d, height h) the formula simplifies. Add a trim allowance to the result; thinned regions change the answer.

In shear spinning material does not move radially, so the blank diameter is taken as roughly equal to the part's largest diameter.

D = √(4A / π)

Cylindrical cup: D ≈ √(d² + 4·d·h)

These formulas are a starting estimate. The blank calculation in metal spinning CAM speeds this up for the selected profile and material; confirm it by measuring the first part.

Spinning ratio and number of passes

The spinning ratio is the blank diameter divided by the mandrel (or part) diameter. The larger the ratio, the further the sheet has to travel onto the mandrel and the more material gathers in the flange — so more passes and a more careful pass plan are needed.

Every material and thickness has a limiting spinning ratio. It depends on formability, the ratio of thickness to diameter, the roller nose radius and the pass plan. Multi-pass spinning generally allows larger deformation than single-stroke deep drawing of the same material.

β = D₀ / d

D₀: blank diameter · d: mandrel diameter

Use supplier data and your own trials for limits; no single number holds for every condition.

Principles of pass design

In conventional spinning the part is not formed in one stroke but through a series of passes. Each pass brings the sheet closer to the mandrel; the final pass follows the mandrel profile with a gap equal to the sheet thickness.

The number and spacing of passes depend on formability, sheet thickness, the spinning ratio and the part geometry. Asking too much deformation in one pass raises the risk of flange wrinkling or wall cracking.

  • Forward passes lay the sheet outward from the mandrel; back passes gather the flange and reduce wrinkling.
  • Work-hardening materials such as stainless steel may need intermediate annealing between passes.
  • Pass angle and spacing can vary along the part; critical zones get denser passes.
  • Approach, retract and safety clearances must be defined explicitly to avoid mandrel collisions.

Roller and mandrel: tooling data that shapes the program

The mandrel carries the inner form of the part, and the profile in the DXF is usually the mandrel surface. The tailstock or follower clamps the blank against the mandrel so they rotate together.

The roller nose radius affects both surface finish and forming force. The program drives the roller centre, not its contact point, so the toolpath must be offset from the mandrel profile by the sheet thickness and the roller radius.

When the roller changes, the mandrel is remade or a different sheet thickness is used, the program must be updated. In CAM these values are settings, so the path can simply be recalculated.

Spindle axisMandrelBlankTailstockRollerRoller centre path
Mandrel, blank, tailstock and roller. The program drives the roller centre.

How do you program a CNC spinning lathe?

Three methods are common. In teach-in (playback) the operator drives the roller on the machine with a joystick or handwheel and the control records and replays the motion. The program is made at the machine, which cannot produce meanwhile.

The second method is writing G-code by hand. Each pass coordinate is calculated and typed; when the profile changes, much of the program has to be rewritten, and the risk of errors is high.

The third is metal spinning CAM, also called offline programming for spinning lathes. The software reads the mandrel profile from the drawing, plans the passes, shows the motion in simulation and outputs G-code for your control. Programs are prepared at a desk while the machine keeps producing. General lathe CAM is built for machining and does not directly support spinning passes or back passes.

G-code structure for spinning lathes

Spinning lathes follow a turning axis layout: Z runs along the spindle axis and X is radial (radius or diameter). A program sets units (G21 mm), coordinate mode (G90 absolute), spindle speed (S, M03) and feed (F); motion uses G00 (rapid), G01 (linear) and G02/G03 (arcs).

Whether arcs use R or centre offsets (I/J/K), whether X is diameter or radius, and whether lines are numbered depend on the control; on FANUC turning controls X is usually a diameter. The post-processor in CAM adapts these details to your machine. This short example shows the structure of a single pass:

SpindlePartZ (spindle axis)X (diameter / radius)
Axis layout of a spinning lathe: Z along the spindle, X radial (radius or diameter).
G21 G90            (mm, absolute coordinates)
G97 S600 M03       (constant rpm, spindle forward)
G00 X160 Z5        (rapid to pass start)
G01 X150 Z-10 F900 (linear feed)
G02 X110 Z-45 R70  (arc)
G01 X96 Z-70
G00 X180 Z20       (retract)
M05                (spindle stop)
M30                (end of program)

The example only shows structure; the values are not valid for any part, material or machine and must not be used in production.

Step-by-step workflow with metal spinning CAM

A typical programming workflow with KSOTech Metal Spinning CNC CAM:

  • Upload the mandrel or part profile as DXF and choose the material.
  • Mark the start and end points on the profile.
  • Calculate the blank diameter and review annealing warnings.
  • Generate conventional passes with automatic mandrel setup; adjust shear regions and back passes if needed.
  • Fine-tune passes with the manual editing tools.
  • Watch the motion in simulation and check the estimated time.
  • Download G-code with the post-processor for your control.
  • Validate the first part on the machine at reduced feed.

Common defects: wrinkling, cracking, mandrel collisions

Most problems in metal spinning trace back to a few typical programming mistakes:

  • Flange wrinkling: the pass step is too large, back passes are missing or the sheet is thin. More passes and added back passes usually help.
  • Wall cracking or tearing: excessive thinning, work hardening or a sudden change of direction. Soften the pass angle and plan intermediate annealing if needed.
  • Mandrel collision: roller radius or sheet thickness not reflected in the path, or the wrong X diameter/radius mode. Check mandrel clearance in simulation.
  • Surface marks: feed and roller nose radius may not match; plan the final passes more finely.
  • Dimensional deviation: springback and mandrel clearance make the part differ slightly from the mandrel; measure the first part and correct the program.

Checklist before production

Check these points before sending a metal spinning program to the machine:

  • Do units (mm/inch) and X diameter/radius mode match the machine?
  • Are the roller nose radius and sheet thickness reflected correctly in the path?
  • Are approach, retract and mandrel clearances free of collision risk?
  • Are spindle speed and feed suitable for the material and part diameter?
  • Is the arc format (R or I/J/K) what the control expects?
  • Will the first run be a dry run or at reduced feed?

Frequently asked questions

What is a metal spinning program?

It is the program that defines the roller motion on a CNC spinning lathe, usually as G-code. Software that prepares it is called metal spinning CAM.

Is metal spinning programming hard to learn?

Writing good programs by hand or by teach-in takes years of experience. CAM shortens this by automating pass planning and G-code output; process knowledge and machine validation are still required.

Can ordinary lathe CAM be used for spinning?

General lathe CAM generates toolpaths for cutting; it has no forming concepts such as multi-pass spinning, back passes or shear spinning. A spinning program therefore needs heavy manual editing or a spinning-specific CAM.

What is the difference between shear and conventional spinning?

Conventional spinning keeps wall thickness roughly constant and forms the part over many passes. Shear spinning thins the wall deliberately; for cones the thickness follows t = t₀·sin α.

Why does the blank diameter matter?

Too small a blank leaves the part short; too large raises flange wrinkling risk and wastes material. The surface-area estimate is a good start; correct it by measuring the first part.

This guide is for general information. Process parameters depend on material, machine and tooling and must be validated by a qualified expert before production.